Threaded Holes Guidelines

Our CNC machining service provides the ability to easily add threaded features to milled and turned parts. Threads are specified within our automated interactive quotes. When a quote is returned, the 3D display will show which thread types are possible for each feature. Different threads (where possible) or no threads can be selected on a feature-by-feature basis. View a sample quote to explore a 3D model with threads.

For those having trouble with the interactive display, a 3D PDF is included in the demo quote that shows the thread options available. After an order is placed, an order confirmation will be emailed with the thread sizes selected. Please review the order confirmation for accuracy.

Milled vs. Turned Parts

We offer a limited selection of UNF, UNC, and metric threads for machining along with coil and key inserts (but do not supply or install the inserts). On both milled and turned parts, threaded holes must be modelled at the proper diameter, however, threading options differ for milled and turned parts. Automatic external threads are not available for milling at this time. It is possible (but not recommended) to obtain external threads on milled parts, but the threads must be modelled. External threads are machined using our standard ball and flat end mills and the smallest external thread that produces reasonable results in our milling process is roughly M12 or UNC ½”-13 (½” Unified Course by 13 Thread Per Inch (TPI)). Threaded holes on turned parts are also available and external threads are offered on the axial diameters. Simply model the nominal diameter; do not model the threads.

All of our available selections are listed in the guide below. If you have any issues or questions please contact an applications engineer at [email protected] or +44 (0) 1952 683047.

THREADING CONSIDERATIONS
  • We may thread a through hole or continuous outer diameter from either side of the part. If the depth of the hole or length of the outer diameter is deeper than our tools can reach, we will offer to thread both ends of the feature. It should be assumed these threads will not be continuous. See our maximum reach tab section for more information.
  • All threads will be right handed. Left-handed threads, and diameter and pitches not shown in the table cannot be produced with our machining processes at this time.
  • We may be unable to thread features that are obstructed by other elements on a part or that are obstructed by our fixturing. If a feature cannot be threaded, no thread options will be offered for that feature on the quote.
  • Threaded features are not available for parts loaded in the .STL format.

 

Key Inserts

threaded holes image illustration for key inserts

* Milling Only

OD Threads

illustration of cnc machining OD threaded holes

* Turning Only

THREADING: MAXIMUM REACH

Example 1:

This is a cross-section view of a through hole that isthreaded from one side. In this case, the hole depth exceeds the reach of the tool. The result is an unthreaded section that is opposite the side selected

Example 2:

This is a cross-section view of a through hole that is threaded from one side. In this case, the hole depth does not exceed the reach of the tool. The result is the threads will be formed across the entire length of the hole.

Example 3:

This is a cross-section view of a through hole that is threaded from two sides. In this case, the hole depth is too long to reach from one side only. However, it can be reached past the centre from either side. If this hole is selected to be threaded from both sides, there will be a discontinuity in the middle of the hole. This means that a bolt can only be threaded to roughly half the depth of the hole.

Example 4:

This is a cross-section view of a through hole that is threaded from both sides. This is similar to Example 3, but the hole is longer and the tool can not reach to the center from either side. In this case, the hole will be threaded to the maximum reach from both sides, leaving an un-threaded section in the middle.

Example 5:

This is a cross-section view of a blind hole (a hole that has a bottom/doesn’t pass through the part). In this case, the hole is less than the full reach and threading will stop roughly 0.010 in. off the bottom. If the hole is deeper than the tool can reach, threads will be cut as deep as possible.

Example 6:

A designer may add a point at the bottom of a blind hole. In most cases, this represents the point left if a pilot hole is drilled with a drill bit. It may also serve a function to their design, or provide an area for chips that are generated during the threading process to fall. If this point is added to the model, the threading will stop roughly 0.010 in. above the start of the point angle.

Internal Metric

Thread Pitch

 

 Process Max Thread depth /mm. CAD Ø * Eligible Ø /mm Clearance Ø /mm
MILLING TURNING MIN MAX 

Internal metric: standard or coarse

M1.6 x 0.35**

 Soft** X 3.00 1.25 1.22 1.32 1.65

M2 x0.4

  ✓ X 5.08 1.60 1.57 1.68 2.05

M2.5 x 0.45

  ✓ X 5.08 2.05 2.01 2.14 2.60

M3 x 0.5

 ✓ ✓ 7.62 2.50 2.46 2.60 3.10

M3.5 x 0.6

 ✓ ✓ 10.16 2.90 2.85 3.01 3.60

M4 x 0.7

 ✓ ✓ 10.16 3.30 3.24 3.42 4.10

M5 x 0.8

 ✓ ✓ 15.24 4.20 4.14 4.33 5.10

M6 x 1.0

 ✓ ✓ 16.51 5.00 4.92 5.15 6.10

M8 x 1.25

 ✓ ✓ 16.51 6.80 6.65 6.91 8.20

M10 x 1.5

 ✓ X 25.40 8.50 8.38 8.68 10.20

M12 x 1.75

 ✓ X 25.40 10.20 10.00 10.44 12.20

Internal metric: fine or special

M8 x 1.0 FINE

 Metal*** ✓ 16.51 7.00 6.91 7.16 8.20

M10 x 1.25 FINE

 Metal*** ✓ 25.40 8.75 8.65 8.91 10.20

M12 x 1.25 FINE

 Metal*** X 25.40 10.75 10.65 10.91 12.20

Obstruction by other features of your part, lead-in treatments, or fixturing requirements may reduce the maximum depth of threads.

* also known as - Pilot Hole Drill Ø

Soft** Only available in soft metals

Metal *** -Only available in metal materials (both hard and soft)

The Minimum Ø and Maximum Ø are the limits our software uses to recognise holes that can be threaded

The maximum thread depth is the limit of our thread cutting tools, starting from the hole face selected, excluding any chamfers of counter bores. If your hole should be deeper than this depth to allow for swarf. Even if you model a deeper hole, only the first portion will be threaded.

Coil insert metric


Thread Pitch

 

 Process Max Thread depth /mm. CAD Ø  Eligible Ø /mm Clearance Ø/mm
MILLING TURNING MIN MAX 

Internal metric: standard or coarse
M2 x 0.4 ✓ X 5.08 2.14 2.09 2.14 2.05
M2.5 x 0.45 ✓ ✓ 7.62 2.6 2.55 2.65 2.60
M3 x 0.5 ✓ ✓ 10.16 3.18 3.11 3.25 3.10
M3.5 x 0.6 ✓ ✓ 15.24 3.7 3.68 3.79 3.60
M4 x 0.7 ✓ ✓ 15.24 4.24 4.15 4.33 4.10
M5 x 0.8 ✓ ✓ 16.51 5.27 5.17 5.37 5.10
M6 x 1.0 ✓ ✓ 16.51 6.31 6.22 6.41 6.10
M8 x 1.25 ✓ ✓ 25.4 8.38 8.27 8.48 8.20
M10 x 1.5 ✓ X 30.48 10.56 10.33 10.56 10.20
M12 x 1.75 ✓ X 30.48 12.51 12.38 12.64 12.20

* also known as Pilot Hole Drill Ø

Outside diameter metric

Thread Pitch

 

 Process Max Thread depth /mm. CAD Ø Eligible Ø /mm Clearance Ø/mm
MILLING TURNING MIN MAX 

Metric outside diameter: standard or coarse

M3 x 0.5

 X ✓ 7 3.5 3.35 3.53 3.16

M4 x 0.7

 X ✓ 8 4 3.84 4.03 4.10

M5 x 0.8

 X ✓ 10 5 4.83 5.03 5.10

M6 x 1.0

 X ✓ 12 6 5.79 6.02 6.10

M8 x 1.25

 X ✓ 16 8 7.76 8.03 8.20

M10 x 1.5

 X ✓ 20 10 9.73 10.03 10.20

M12 x 1.75

 X* ✓ 24 12 11.7 12.02 12.20

M14 x 2.0

 X* ✓ 28 14 13.68 14.03 14.25

M16 x 2.0

 X* ✓ 32 16 15.68 16.02 16.25

M20 x 2.5

 X* ✓ 40 20 19.62 20.03 20.25

Metric outside diameter: fine or special

M8 x 1.0 FINE

 X ✓ 16 8 7.8 8.03 8.20

M10 x 0.75 SP

 X ✓ 20 10 9.84 10.03 10.20

M10 x 1.25 FINE

 X X 20 10 9.76 10.03 10.20

M12 x 1.25 FINE

 X ✓ 24 12 11.76 12.02 12.20

M12 x 1.0 SP

 X ✓ 24 12 11.79 12.02 12.20

M12 x 1.5 SP

 X** ✓ 24 12 11.73 12.02 12.20

M14 x 1.5 FINE

 X** ✓ 28 14 13.73 14.03 14.25

M15 x 1.0 SP

 X ✓ 30 15 14.79 15.03 15.25

M16 x 1.5 FINE

 X** ✓ 32 16 15.73 16.02 16.25

M17 x 1.0 SP

 X ✓ 34 17 16.79 17.03 17.25

M18 x 1.5 FINE

 X** ✓ 36 18 17.73 18.03 18.25

M20 x 1.5 FINE

 X** ✓ 40 20 19.73 20.03 20.25

*also known as - Pilot Hole Drill Ø

** On a 3 or 5-axis mill larger exteral threads can be cut with a ball nose cutter… refer to Special threads.

Key Insert Inch

Thread Pitch

 

 Process Max Thread depth /mm. CAD Ø Eligible Ø /mm Clearance Ø/mm
MILLING TURNING MIN MAX 

Inch key insert: Unified fine UNF

#10-32

 ✓ X 0.600 0.162 0.160 0.164 N/A

#12-28

 ✓ X 0.600 0.189 0.186 0.191 N/A

1/4-28

 ✓ X 0.650 0.229 0.227 0.231 N/A

Inch key insert: Unified coarse UNC

#8-32

 ✓ X 0.400 0.135 0.133 0.137 N/A

5/16-18

 ✓ X 0.650 0.274 0.271 0.276 N/A

3/8-16

 ✓ X 1.000 0.334 0.331 0.336 N/A

7/16-14

 ✓ X 1.000 0.399 0.396 0.401 N/A

1/2-13

 ✓ x 1.000 0.455 0.452 0.457 N/A

* * also known as - Pilot Hole Drill Ø